Chapters
- 1 Getting started
- 2 The interface
- 3 Coordinate systems and conventions
- 4 Modelling
- 5 Materials
- 6 Sections
- 7 Supports, releases and modifiers
- 8 Loads
- 9 Load combinations
- 10 Meshing
- 11 Static analysis
- 12 Dynamic and seismic analysis
- 13 Results
- 14 Design
- 15 Scripting and the AI model builder
- 16 Import and export
- 17 Verification
- 18 Scope and limits
- 19 Troubleshooting
- 20 Glossary and notation
On this page
The FEA Tool checks a model before every run and explains, in plain words, anything that would stop the analysis or make its results meaningless. This chapter lists those messages by topic, with their causes and fixes, and then covers results that run but look wrong. Some messages are shortened here; on screen each one names the node, member, area or case concerned, shown below in angle brackets such as ⟨node⟩.
19.1 Before the analysis: the model
| What the tool says | Cause and fix |
|---|---|
| There is no model to analyse. | Start from a template, draw a model, run a script or import a file. |
| The model has no nodes yet. | Add nodes and members in the Model tab, or start from a template or a file. |
| The model has nodes but no members or areas, so there is nothing to analyse. | Draw members or areas between the nodes. |
| The structure has no supports, so it is free to move. | Add at least one support. A fixed base, or pins with a roller, are enough for a stable plane frame; a 3D frame needs restraint in both horizontal directions and against twist. |
| A part of ⟨n⟩ nodes (including node ⟨node⟩) has no support or spring: it is free to move. | A group of members is not connected to the rest. Usually two members cross or meet without a shared node, or a node was placed slightly off a member. Merge the nodes (Merge nodes), divide the members at their intersection (Divide), or add a support. |
| Member ⟨id⟩ has no section. | Assign a section from Code libraries or Frame sections. |
| Member ⟨id⟩ refers to a node that is not in the model. | A node was deleted under a member, or an imported file is incomplete. Delete the member or recreate the node. |
| Member ⟨id⟩ has zero length. | Its two end nodes coincide. Delete it or merge the nodes. |
| Member ⟨id⟩: its end releases leave it unstable on its own (for example torsion or the same shear released at both ends). | Keep torsion, and each shear, fixed at one end at least. |
| A load or combination names a case or object that is not in the model. | Remove the load, or restore the object or case. The message names it. |
| Area ⟨id⟩ has no area: its points lie on one line. | Redraw the area with three or more points that are not in line. |
| Area ⟨id⟩: its edges cross each other; list its points in order around the area. | The corners were clicked out of order. Redraw them in order around the boundary. |
19.2 Before the analysis: loads, mass and inputs
| What the tool says | Cause and fix |
|---|---|
| There are no load cases. | Add a load pattern in the Loads tab; self weight alone counts as a load. |
| Every load case is empty, so the structure would not deflect. | Add loads, or set a self weight multiplier of 1 on the dead load pattern. |
| The model has no mass, so natural periods cannot be found. | Give the materials a density, keep self mass on, or take mass from a load pattern (Loads > Mass, or Analysis > Seismic and dynamic setup > Mass source). |
| The response spectrum table needs at least two valid points (period and Sa). | Check the pasted columns in Analysis > Your own spectra and records. |
| The time history has no ground motion record. | Paste or generate a record in Analysis > Your own spectra and records and pick it as the ground motion. |
| Ritz vectors need a starting load that acts on the mass. | Choose UX, UY or UZ, or a load pattern with loads on parts that carry mass. |
| Buckling needs a load case or combination to scale. | Choose the base loading in the parameters. |
| This model has areas (shells, plates, membranes). | The nonlinear, pushover and nonlinear time history analyses do not take areas. Use a linear type, or replace the slabs by a diaphragm and beams for the nonlinear study. |
| The analysis type is not in your plan. | The type is greyed out in the Analysis tab with the reason. See Pricing. |
| The model is larger than the plan or the analysis allows. | Reduce the mesh, remove detail that does not affect the result, or split the model (Chapter 18). |
Inputs of a seismic code outside the range of the standard are listed under the spectrum plot with the clause. They do not stop a run but should be corrected.
19.3 During the analysis
| What the tool says | Cause and fix |
|---|---|
| The structure is unstable: no stiffness against ⟨direction⟩ at node ⟨node⟩ (a mechanism, a missing support or end releases that free a joint). Add a support or a member there, or remove a release. | The factorisation found a direction with no stiffness. Look at the named node: a pinned joint with every member released, a truss without bracing in one plane, a column pinned at both ends with nothing holding its top, or a member connected only to itself. |
| Load case ⟨name⟩ (or Combination ⟨name⟩): the structure is unstable under its axial forces (load above the elastic buckling load; P-Delta has no solution). | The axial loads exceed the elastic buckling load of the structure. Run a buckling analysis of the same combination: a factor below 1 confirms it. Stiffen the structure, add bracing, or check the loads and their units. |
| No positive buckling factor: the base loading ⟨name⟩ puts no member in compression that can buckle. | The base loading is in tension only, or too small. Choose a combination with compression. |
| Every degree of freedom of the model is restrained. | Not an error: linear static and P-Delta still give the fixed-end forces and reactions. Modal, buckling and dynamic runs need free degrees of freedom. |
| The nonlinear analysis did not converge at a step. | The structure reached a mechanism, or the steps are too large. Use more steps, a smaller target, or displacement control; look at the hinge states at the last converged step. |
| A conditionally stable time integration diverged, or was refused. | Linear acceleration and Wilson-θ below 1.37 need mass on every degree of freedom. Use Newmark average acceleration (the default) or HHT-α. |
| The record or model gives more than 20,000 time steps. | Lengthen the time step (keeping it below about a tenth of the shortest period of interest) or shorten the duration. |
19.4 Messages that report, not stop
These appear under the Run button after a run. Read them, because they say what the engine did for you.
| What the tool says | Meaning |
|---|---|
| Area ⟨id⟩ has no mesh setting, so the automatic mesh is used. | An older model or imported area had no mesh; the automatic mesh was applied. |
| Automatic area mesh: the element size is enlarged to keep the model within the 3000-node analysis limit. | The mesh was coarsened (Section 10.6). Check that the result you need is not sensitive to it, or reduce the meshed area. |
| Frame-edge matching: ⟨n⟩ members along area edges joined to the area mesh at ⟨k⟩ nodes. | Beams on slab edges and mesh lines were connected to the slab (Section 10.4). |
| Members cut at intermediate joints or crossings. | A node on a member's span connected it there (Section 10.2). |
| Members divided into 4 parts for the dynamic or buckling analysis. | The default mesh of these types (Section 10.1). |
| A material is not in the model; the type defaults are used. | Add the material, or check that the defaults (Section 5.4) suit you. |
| Property modifiers are applied to ⟨n⟩ members. | A reminder that the stiffness is not the gross section. |
| A warped quadrilateral (offset ratio above 0.01). | An area's corners are not in one plane; it is analysed on its mean plane with rigid offsets. Split a strongly warped area into triangles or flatter parts. |
| The section ⟨name⟩ is in another region's library. | The section was found in the library of another code. Change the design code or pick a local section before designing. |
| Auto-select list ⟨name⟩: the analysis used ⟨section⟩. | The median section by weight, or the last designed section, was used for the analysis. |
19.5 Results that run but look wrong
Very large displacements in one pattern. The structure is close to a mechanism: a near-zero stiffness that the factorisation did not reject. Look at the deformed shape with a small scale; the part that moves most is the part that is not held. Common causes are a missing brace, a column pinned at both ends in a sway frame, or a slab supported only at the beam ends because the beams were not matched to the mesh.
The sum of the reactions does not match the load. A load acts on a held degree of freedom (it goes straight to the support and still appears), or loads were given in the wrong direction or units. Check the load arrows in the Loads tab and the display units in the status bar.
Moments of the wrong sign or on the wrong axis. Check the local axes of the members (Options > Show local axes) and the roll angle. An I section with has its web along local 2; a column rotated 90° needs .
A beam carries no moment at a column. Its end is released, or it is not connected: it may pass the column without a shared node. Use Divide > At intersections or merge the nodes.
A slab carries load straight to the corners. The slab and its edge beams share no nodes along the edges. Frame-edge matching connects them when the beams lie on the area edges; a beam offset from the edge is not matched.
Peaks in a contour at a column or point support. The elastic solution of a plate is singular at a point support, so the peak grows with mesh refinement. Design from the moment at the face of the support or averaged over a strip.
Periods much longer than expected. Too much mass (a live load factor of 1.0 instead of 0.3, or the mass counted twice) or too little stiffness (property modifiers, releases). Check for the first mode.
A design status of Needs input. The module needs a value the model does not hold: concrete reinforcement, a timber grade strength, or a shear input. Enter it in Design > Design inputs or the section form.
The Python console does not start. Python is loaded from the site, then from a public CDN, on first use. On a network that blocks both, use Retry Python later or write the script in JavaScript, which needs nothing to load.