TensorNodeStart free trial

FEA Tool manual › Chapter 7

Supports, releases and modifiers

Chapters
  1. 1 Getting started
  2. 2 The interface
  3. 3 Coordinate systems and conventions
  4. 4 Modelling
  5. 5 Materials
  6. 6 Sections
  7. 7 Supports, releases and modifiers
  8. 8 Loads
  9. 9 Load combinations
  10. 10 Meshing
  11. 11 Static analysis
  12. 12 Dynamic and seismic analysis
  13. 13 Results
  14. 14 Design
  15. 15 Scripting and the AI model builder
  16. 16 Import and export
  17. 17 Verification
  18. 18 Scope and limits
  19. 19 Troubleshooting
  20. 20 Glossary and notation
On this page
  1. 7.1 Supports
  2. 7.2 Springs
  3. 7.3 Area springs and edge restraints
  4. 7.4 End releases
  5. 7.5 Rigid end offsets
  6. 7.6 Member types
  7. 7.7 Property modifiers
  8. 7.8 Node masses
  9. 7.9 Rigid floor diaphragms

This chapter covers how a model is held and connected: supports and springs at nodes, springs under areas, restraints along area edges, end releases and rigid end offsets of members, member types, property modifiers, extra masses and rigid floor diaphragms.

7.1 Supports

A support holds some of the six degrees of freedom of a node in global axes. The toolbar buttons set the common cases on the selected nodes, and Model > Supports, releases and roll angle offers a few more:

SupportHeldFree
Fixedux,uy,uz,rx,ry,rzu_x, u_y, u_z, r_x, r_y, r_znone
Pinnedux,uy,uzu_x, u_y, u_zrx,ry,rzr_x, r_y, r_z
Roller (vertical only)uzu_zthe rest
Roller (free in X)uy,uzu_y, u_zuxu_x and the rotations
Freenoneall six

The properties panel of a node shows six checkboxes (Ux to Rz) for any other combination. In files and scripts a support can also be written as six letters, F for held and R for released, so FFFRRR is a pin.

7.2 Springs

A node spring adds stiffness to a degree of freedom: kxk_x, kyk_y, kzk_z in kN/m and krxk_{rx}, kryk_{ry}, krzk_{rz} in kNm/rad, in global axes. A spring on a held degree of freedom is ignored. Spring forces are reported as support reactions. A part of the structure held only by springs counts as supported in the model check.

7.3 Area springs and edge restraints

Loads > Area springs places a distributed elastic support under the selected areas: a normal modulus knk_n (along local 3) and optional in-plane moduli k1k_1 and k2k_2, all in kN/m³. Use it for a slab on ground or a tank floor on a Winkler foundation. The modulus is lumped to the nodes of the mesh by the shape functions NaN_a of each element,

ka=kn∫ANa dA(7.1)k_a = k_n \int_A N_a \, dA \tag{7.1}

so a finer mesh gives a smoother pressure. The spring forces are reported as reactions at the mesh nodes, and an area with springs counts as supported in the model check.

In the model file an area can also carry a restraint for each of its edges (edges, in the same forms as a node support). It applies to every node of the mesh on that edge, together with any support of those nodes, and counts as a support in the model check.

7.4 End releases

An end release frees one of the six member end forces at the start (node ii) or end (node jj) of a member, in its local axes: U1 (axial), U2 and U3 (shears), R1 (torsion), R2 and R3 (moments). Set them in the properties panel (checkboxes for start and end) or with the buttons Fixed ends, Pinned both ends, Pinned at start and Pinned at end of Supports, releases and roll angle. Pinned releases R2 and R3.

A released end force is zero; the member's stiffness is condensed so that the end displacement it frees is found from the member's own equilibrium. Some combinations leave a member free to move on its own, for example torsion released at both ends or the same shear released at both ends. The model check refuses them and names the member.

A node where every member is pinned and nothing else holds the rotation has a rotational degree of freedom with no stiffness. The analysis holds such degrees of freedom and lists them, so a truss with pinned members runs without a support at every joint.

7.5 Rigid end offsets

A rigid end offset models the depth of a joint: the part of a beam inside a column, or of a column inside a deep beam. Property modifiers, end offsets and mesh sets the offset lengths oio_i and ojo_j at the two ends of the selected members and a rigid zone factor rzr_z (0 to 1). The flexible length of the member is

Lf=L−rz (oi+oj)(7.2)L_f = L - r_z\,(o_i + o_j) \tag{7.2}

With rz=1r_z = 1 (the default) the whole offset is rigid; with rz=0.5r_z = 0.5 half of it is. Loads on a rigid zone go straight to the node as a force and a moment. Results are given at stations along the flexible part, measured from node ii. The nonlinear and pushover analyses do not use end offsets and say so.

7.6 Member types

TypeBehaviour
Frameaxial force, two shears, torsion and two moments; shear deformation included where the section has shear areas
Trussaxial force only: both end rotations and the torsion at end jj are released
Cableaxial force only, as a truss; in the nonlinear analyses it carries tension only

7.7 Property modifiers

Property modifiers scale the section properties of selected members or areas, or of every member or area that uses a section. Use them for cracked concrete, for a deck that should not act as a diaphragm chord, or for a study of sensitivity.

Frame modifiers. AA, As2A_{s2}, As3A_{s3}, JJ, I22I_{22}, I33I_{33}, mass and weight. The modifiers of a section and of a member multiply. AA, AsA_s, JJ and II change the stiffness only; mass changes the mass and weight the self weight. The run lists the members with modifiers in its messages.

Cracked modifiers. The section designer and the property modifier panel can set the cracked-section factors of the code for beams, columns, walls and slabs, with the axial load ratio where the code makes them depend on it.

Area modifiers. f11f_{11}, f22f_{22}, f12f_{12} scale the membrane stiffness, m11m_{11}, m22m_{22}, m12m_{12} the bending stiffness, v13v_{13}, v23v_{23} the transverse shear stiffness, with mass and weight, in the area's local axes:

C11→f11C11,C22→f22C22,C33→f12C33,C12→f11f22  C12(7.3)C_{11} \to f_{11} C_{11}, \quad C_{22} \to f_{22} C_{22}, \quad C_{33} \to f_{12} C_{33}, \quad C_{12} \to \sqrt{f_{11} f_{22}}\; C_{12} \tag{7.3}

and likewise for the bending terms DD with m11m_{11}, m22m_{22} and m12m_{12}. Setting f22=0f_{22} = 0 removes the in-plane stiffness along local 2, for example for a roof deck spanning one way that must not act as a chord flange. The modifiers of an area section and of the area multiply.

7.8 Node masses

A node can carry a lumped mass [mx,my,mz,Ixx,Iyy,Izz][m_x, m_y, m_z, I_{xx}, I_{yy}, I_{zz}] in tonnes and t·m², or one number for mx=my=mzm_x = m_y = m_z. Use it for plant, tanks or a floor mass that is not modelled by loads. Node masses add to the mass source of Section 8.10.

7.9 Rigid floor diaphragms

Analysis > Seismic and dynamic setup > Diaphragms sets how floors are idealised in the dynamic and seismic analyses:

  • Rigid: at each level above the base, a master joint is added at the centre of mass of the level (with uzu_z, rxr_x and ryr_y held), and every joint of the level follows it in uxu_x, uyu_y and rzr_z. The masters appear in the displacement results but not as supports.
  • Semi-rigid (or none): no constraint; the levels are used only to collect storey results.

Levels are found from the node elevations within a tolerance (0.05 m by default), or listed; joints can be excluded. The constraint of a joint at plan position (x,y)(x, y) to the master at (xm,ym)(x_m, y_m) is

ux−umx+(y−ym) θm=0,uy−umy−(x−xm) θm=0,rz−θm=0(7.4)u_x - u_{mx} + (y - y_m)\,\theta_m = 0, \qquad u_y - u_{my} - (x - x_m)\,\theta_m = 0, \qquad r_z - \theta_m = 0 \tag{7.4}

These equations are enforced by stiff links (a penalty of 10610^6 times the largest translational stiffness term, with the rotation row scaled by the square of the plan size), which keeps the constraint error near 10−610^{-6}. With lump at the master, the lateral mass of each rigid level is lumped at its master with the polar moment Ip=∑mr2I_p = \sum m r^2 about the centre of mass.