Chapters
- 1 Getting started
- 2 The interface
- 3 Coordinate systems and conventions
- 4 Modelling
- 5 Materials
- 6 Sections
- 7 Supports, releases and modifiers
- 8 Loads
- 9 Load combinations
- 10 Meshing
- 11 Static analysis
- 12 Dynamic and seismic analysis
- 13 Results
- 14 Design
- 15 Scripting and the AI model builder
- 16 Import and export
- 17 Verification
- 18 Scope and limits
- 19 Troubleshooting
- 20 Glossary and notation
On this page
This chapter covers how a model is held and connected: supports and springs at nodes, springs under areas, restraints along area edges, end releases and rigid end offsets of members, member types, property modifiers, extra masses and rigid floor diaphragms.
7.1 Supports
A support holds some of the six degrees of freedom of a node in global axes. The toolbar buttons set the common cases on the selected nodes, and Model > Supports, releases and roll angle offers a few more:
| Support | Held | Free |
|---|---|---|
| Fixed | none | |
| Pinned | ||
| Roller (vertical only) | the rest | |
| Roller (free in X) | and the rotations | |
| Free | none | all six |
The properties panel of a node shows six checkboxes (Ux to Rz) for any other combination. In files and scripts a support can also be written as six letters, F for held and R for released, so FFFRRR is a pin.
7.2 Springs
A node spring adds stiffness to a degree of freedom: , , in kN/m and , , in kNm/rad, in global axes. A spring on a held degree of freedom is ignored. Spring forces are reported as support reactions. A part of the structure held only by springs counts as supported in the model check.
7.3 Area springs and edge restraints
Loads > Area springs places a distributed elastic support under the selected areas: a normal modulus (along local 3) and optional in-plane moduli and , all in kN/m³. Use it for a slab on ground or a tank floor on a Winkler foundation. The modulus is lumped to the nodes of the mesh by the shape functions of each element,
so a finer mesh gives a smoother pressure. The spring forces are reported as reactions at the mesh nodes, and an area with springs counts as supported in the model check.
In the model file an area can also carry a restraint for each of its edges (edges, in the same forms as a node support). It applies to every node of the mesh on that edge, together with any support of those nodes, and counts as a support in the model check.
7.4 End releases
An end release frees one of the six member end forces at the start (node ) or end (node ) of a member, in its local axes: U1 (axial), U2 and U3 (shears), R1 (torsion), R2 and R3 (moments). Set them in the properties panel (checkboxes for start and end) or with the buttons Fixed ends, Pinned both ends, Pinned at start and Pinned at end of Supports, releases and roll angle. Pinned releases R2 and R3.
A released end force is zero; the member's stiffness is condensed so that the end displacement it frees is found from the member's own equilibrium. Some combinations leave a member free to move on its own, for example torsion released at both ends or the same shear released at both ends. The model check refuses them and names the member.
A node where every member is pinned and nothing else holds the rotation has a rotational degree of freedom with no stiffness. The analysis holds such degrees of freedom and lists them, so a truss with pinned members runs without a support at every joint.
7.5 Rigid end offsets
A rigid end offset models the depth of a joint: the part of a beam inside a column, or of a column inside a deep beam. Property modifiers, end offsets and mesh sets the offset lengths and at the two ends of the selected members and a rigid zone factor (0 to 1). The flexible length of the member is
With (the default) the whole offset is rigid; with half of it is. Loads on a rigid zone go straight to the node as a force and a moment. Results are given at stations along the flexible part, measured from node . The nonlinear and pushover analyses do not use end offsets and say so.
7.6 Member types
| Type | Behaviour |
|---|---|
| Frame | axial force, two shears, torsion and two moments; shear deformation included where the section has shear areas |
| Truss | axial force only: both end rotations and the torsion at end are released |
| Cable | axial force only, as a truss; in the nonlinear analyses it carries tension only |
7.7 Property modifiers
Property modifiers scale the section properties of selected members or areas, or of every member or area that uses a section. Use them for cracked concrete, for a deck that should not act as a diaphragm chord, or for a study of sensitivity.
Frame modifiers. , , , , , , mass and weight. The modifiers of a section and of a member multiply. , , and change the stiffness only; mass changes the mass and weight the self weight. The run lists the members with modifiers in its messages.
Cracked modifiers. The section designer and the property modifier panel can set the cracked-section factors of the code for beams, columns, walls and slabs, with the axial load ratio where the code makes them depend on it.
Area modifiers. , , scale the membrane stiffness, , , the bending stiffness, , the transverse shear stiffness, with mass and weight, in the area's local axes:
and likewise for the bending terms with , and . Setting removes the in-plane stiffness along local 2, for example for a roof deck spanning one way that must not act as a chord flange. The modifiers of an area section and of the area multiply.
7.8 Node masses
A node can carry a lumped mass in tonnes and t·m², or one number for . Use it for plant, tanks or a floor mass that is not modelled by loads. Node masses add to the mass source of Section 8.10.
7.9 Rigid floor diaphragms
Analysis > Seismic and dynamic setup > Diaphragms sets how floors are idealised in the dynamic and seismic analyses:
- Rigid: at each level above the base, a master joint is added at the centre of mass of the level (with , and held), and every joint of the level follows it in , and . The masters appear in the displacement results but not as supports.
- Semi-rigid (or none): no constraint; the levels are used only to collect storey results.
Levels are found from the node elevations within a tolerance (0.05 m by default), or listed; joints can be excluded. The constraint of a joint at plan position to the master at is
These equations are enforced by stiff links (a penalty of times the largest translational stiffness term, with the rotation row scaled by the square of the plan size), which keeps the constraint error near . With lump at the master, the lateral mass of each rigid level is lumped at its master with the polar moment about the centre of mass.