TensorNodeStart free trial

FEA Tool manual › Chapter 6

Sections

Chapters
  1. 1 Getting started
  2. 2 The interface
  3. 3 Coordinate systems and conventions
  4. 4 Modelling
  5. 5 Materials
  6. 6 Sections
  7. 7 Supports, releases and modifiers
  8. 8 Loads
  9. 9 Load combinations
  10. 10 Meshing
  11. 11 Static analysis
  12. 12 Dynamic and seismic analysis
  13. 13 Results
  14. 14 Design
  15. 15 Scripting and the AI model builder
  16. 16 Import and export
  17. 17 Verification
  18. 18 Scope and limits
  19. 19 Troubleshooting
  20. 20 Glossary and notation
On this page
  1. 6.1 Section properties used by the analysis
  2. 6.2 Section libraries
  3. 6.3 Sections from a name
  4. 6.4 Parametric frame sections
  5. 6.5 Section designer
  6. 6.6 Section drawing
  7. 6.7 Prestress
  8. 6.8 Auto-select lists
  9. 6.9 Area sections

A frame section gives a member its area, second moments of area, torsion constant, shear areas and shape; an area section gives an area its type and thickness. The FEA Tool takes frame sections from the steel libraries of four code regions, from parametric forms, from a section designer for steel, reinforced concrete and composite members, and from a drawing canvas on which any section is drawn with the cursor. This chapter covers each source, the properties computed, auto-select lists and area sections.

6.1 Section properties used by the analysis

The frame element reads these properties of a section, in its local axes (Section 3.2):

PropertySymbolUse
cross-section areaAAaxial stiffness, self weight, mass
shear areas along 2 and 3As2A_{s2}, As3A_{s3}shear deformation; zero turns it off for that direction
torsion constantJJSaint-Venant torsional stiffness GJGJ
second moments of areaI33I_{33}, I22I_{22}, I23I_{23}bending stiffness about the major and minor axes
warping constantIwI_wdesign modules; not used by the frame element
elastic and plastic moduliS33S_{33}, S22S_{22}, Z33Z_{33}, Z22Z_{22}stresses, plastic hinges, design

The section table of the form lists 13 properties with the mass per metre: AA, As2A_{s2}, As3A_{s3}, JJ, I33I_{33}, I22I_{22}, I23I_{23}, S33S_{33}, S22S_{22}, Z33Z_{33}, Z22Z_{22}, r33r_{33}, r22r_{22}.

6.2 Section libraries

Model > Code libraries holds the steel sections of each region: AS (AS/NZS 3679.1 and AS/NZS 1163 hot rolled, welded and hollow sections), US and CA (the AISC Shapes Database in US and CSA names), and EU (EN 10365, EN 10210-2 and EN 10056: IPE, HE, hollow sections and angles). Type in the search box, filter by shape, pick a section and press Assign section to give it to the selected members.

Names are matched without regard to spaces and punctuation, so 310UB40.4 and 310 UB 40.4 are the same section, as are HEA200, HE200A and HE 200 A. A section found only in another region's library is accepted and the properties panel says so, for example that IPE 300 is a European section in an Australian model; change the design code or pick a local section before you design.

For AS sections, the torsion constant, minor-axis moduli and shear areas are computed from the plate dimensions of the section.

6.3 Sections from a name

A section name that describes a solid or a timber size is read directly:

NameSection
300x500RC, R300x600concrete rectangle 300 mm wide and 500 (600) mm deep
400x400RC colconcrete rectangle with the column role
D450, 450 dia RCconcrete circle of 450 mm diameter
90x45MGP10timber rectangle of the named grade
C600circle of 600 mm diameter

For a name without an orientation, the larger dimension is the depth (along local 2).

6.4 Parametric frame sections

Model > Frame sections defines a section by its shape and dimensions. The shapes are rectangle, circle, I (with unequal flanges), box, pipe, channel, angle, double angle, tee, general (properties typed in) and library. The form shows a sketch with the local axes 2 and 3, the 13 properties and the mass, and keeps a colour and notes with the section. Save section adds it to the model, Save and assign to the selection gives it to the selected members.

The frame section form for a 100 mm box section with its sketch and computed properties
Figure 6.1 Model > Frame sections: a thin-walled box section, its sketch with local axes and its 13 properties. J is found by the Bredt formula for a closed thin wall.

Torsion constant. For a solid rectangle of depth dd and width bb with d≥bd \ge b, the form uses the Saint-Venant series (Timoshenko and Goodier):

J=d b33[1−192 bπ5d∑n=1,3,5,…1n5tanh⁡nπd2b](6.1)J = \frac{d\,b^3}{3}\left[1 - \frac{192\,b}{\pi^5 d}\sum_{n=1,3,5,\ldots} \frac{1}{n^5}\tanh\frac{n\pi d}{2b}\right] \tag{6.1}

Solids read from a section name (such as R300x600) use the close approximation of Roark (Table 10.7, case 4):

J=d b3[13−0.21 bd(1−b412d4)](6.2)J = d\, b^3\left[\frac{1}{3} - 0.21\,\frac{b}{d}\left(1 - \frac{b^4}{12 d^4}\right)\right] \tag{6.2}

For a thin-walled closed section (box, pipe) the Bredt formula is used on the centre line of the wall,

J=4Am2∮dst(6.3)J = \frac{4 A_m^2}{\oint \dfrac{ds}{t}} \tag{6.3}

with AmA_m the area enclosed by the mid-line of the wall and tt the wall thickness. For an open thin-walled section, J=∑biti3/3J = \sum b_i t_i^3/3 over its plates. The form states which rule it used.

Shear areas. The form computes the shear areas as follows:

ShapeAs2A_{s2} (along local 2)As3A_{s3} (along local 3)
rectangle5A/65A/65A/65A/6
circle0.9A0.9A0.9A0.9A
pipeA/2A/2A/2A/2
I, teed twd\,t_w5/65/6 of the flange areas
channeld twd\,t_w5/65/6 of the two flange areas
box2 d tw2\,d\,t_w2 b tf2\,b\,t_f
angle5/65/6 of the vertical leg5/65/6 of the horizontal leg

Concrete reinforcement. A concrete rectangle or circle can carry its reinforcement for the design: the role (beam or column), the clear cover to the ties, the bar diameter and count on each face (or around a circle), the top and bottom bars of a beam, the tie diameter and spacing, and ties or a spiral. The member design modules read these values; the analysis uses the gross section unless modifiers are set (Section 7.7).

6.5 Section designer

Model > Section designer builds a section from a parametric definition and computes its full set of properties, its cracked properties and its nonlinear response. The kinds are:

KindShapes and data
SteelI (unequal flanges), channel, angle, tee, box, pipe, rectangle, circle, polygon
Reinforced concreterectangle, circle, T and L, with cover, ties, bars on each face or around a circle, extra bars, and confinement
Compositea steel I beam with a concrete slab: effective width from the span and spacing by code, profiled deck (rib height, width and spacing, ribs across or along the beam), slab reinforcement, degree of shear connection, short or long term
Concrete-filled tubea rectangular or circular steel tube filled with concrete
Encaseda steel section encased in reinforced concrete

The properties include the centroid, I33I_{33}, I22I_{22}, I23I_{23}, the principal moments of area and their angle, elastic and plastic moduli, the plastic neutral axis, JJ, IwI_w, the shear centre and the shear areas. For composite sections the transformed second moment of area is given for short and long term with the modular ratios, and the effective II for partial shear connection. For concrete sections the cracked second moment of area IcrI_{cr} is given for sagging and hogging, with the effective second moment of area IeI_e of the code.

Stiffness for analysis. The section designer can set the stiffness the analysis uses: gross, the cracked-section factors of the code for beams, columns, walls and slabs, the cracked section, or the effective section. It writes the choice as property modifiers on the section, with a note of the basis.

Moment-curvature. The section is divided into fibres, each following the stress-strain curve of its material (Section 5.5). With stresses and strains positive in tension and for a chosen axial force, the curvature κ\kappa is increased step by step and the moment is found from equilibrium of the fibre stresses:

N=∑kσk(εk) Ak,M3=−∑kσk(εk) Ak yk,εk=ε0−κ3 yk(6.4)N = \sum_k \sigma_k(\varepsilon_k)\,A_k, \qquad M_3 = -\sum_k \sigma_k(\varepsilon_k)\,A_k\,y_k, \qquad \varepsilon_k = \varepsilon_0 - \kappa_3\, y_k \tag{6.4}

where yky_k is the position of fibre kk along local 2 and ε0\varepsilon_0 the axial strain at the reference point, found so that NN equals the given force. The curve marks the events: cracking, first yield, cover spalling, crushing, the ultimate concrete strain εcu\varepsilon_{cu}, the compression limit of the bars and bar fracture. A bilinear idealisation gives the first yield moment, the nominal moment, the yield and ultimate curvatures and the curvature ductility.

The Results tab with the moment-curvature curve of one hinge section, rising in a straight line and then bending over as the steel yields
Figure 6.2 The moment-curvature curve of a hinge section from a pushover run; it is straight while the section is elastic and bends over as the steel yields.

Interaction diagram. The P-M interaction curve is found by strain compatibility with the extreme fibre at εcu\varepsilon_{cu} and the rectangular stress block of the code, as nominal values without strength reduction factors, with moments about the centroid of the gross section. The squash load and the balance point are marked.

6.6 Section drawing

Model > Section drawing is a canvas on which a section of any shape is drawn with the cursor, in millimetres. Use it for bridge girders, precast units, built-up and composite sections, and sections with holes.

The section drawing canvas with a rectangular concrete section, a hole and three bars, and its gross properties listed below
Figure 6.3 Model > Section drawing: a concrete rectangle with a hole and three bars, and its properties. Every shape keeps its own material.

Tools. Select or move, pan, polygon, rectangle, circle, standard steel shape, bridge template, single bar, line of bars, perimeter bars and tendon. The wheel zooms and the middle button pans. Points snap to a grid (50 mm by default) and to the vertices of other shapes, and can be typed as x, y or @dx, dy. The drawing axes are local 2 up and local 3 to the right, seen from end ii of the member.

Bridge templates. I-girder, bulb-tee, box with one or more cells, closed or open trough, voided slab, and composite (a girder with a haunch and a deck cast in stage 2). A template stays editable through its parameters after it is placed.

Materials and holes. Every shape has its own material (concrete, steel, reinforcing bar, tendon or other) and a stage (1 or 2). A shape marked as a hole cuts the shapes below it.

Overlapping shapes. Shapes are resolved in drawing order. A solid joins the region of its own material and stage, cuts the regions of other materials below it, and a hole cuts every region below it. The panel names each overlap it resolved. Circles are drawn as 192-sided polygons, but a circle that no other shape cuts is integrated exactly.

Properties. The properties are given on a chosen basis: gross (bars left out), transformed short term, or transformed long term, about the reference material of the section. They include those of the section designer, the stage 1 section of a composite girder, the cracked section in sagging and hogging, and the totals of bars and tendons.

Saving. A drawn section is saved to the model's sections (and can then be assigned to members) or to a JSON section library that other models can read. In the 3D view a member with a drawn section is drawn with its true outline. The fibre tools of the section designer (moment-curvature and interaction) accept drawn sections unchanged.

6.7 Prestress

Tendons are placed on the drawing canvas by position (or by eccentricity), number of strands and strand area, with the jacking stress or force and the losses at transfer and in the long term, as percentages. The panel gives the prestress forces at jacking, transfer and service, the eccentricity of the tendon group, and the stresses at the top and bottom fibres at transfer and in service under the moments you give: the moment at transfer, the moment of the second-stage dead load, and the moments of the permanent and total service loads.

The fibre stress follows from the force PP at eccentricity ee below the centroid and the moment MM (sagging positive):

σ(y)=−PA+P e yI−M yI(6.5)\sigma(y) = -\frac{P}{A} + \frac{P\,e\,y}{I} - \frac{M\,y}{I} \tag{6.5}

with yy measured upwards from the centroid and compression negative. For a composite girder, the stage 1 section carries the prestress and the self weight, and the composite section carries the second-stage loads.

Each stress is compared with the limit of the chosen standard, and the panel gives the clause:

Table 6.1 Stress limits applied to prestressed sections
StandardAt transferIn service
AS 3600compression 0.6fcp′0.6f'_{cp} for a rectangular section with a triangular stress distribution, else 0.5fcp′0.5f'_{cp} (8.1.6.2)tension 0.25fc′0.25\sqrt{f'_c}, or 0.6fc′0.6\sqrt{f'_c} with bonded steel (8.6.3)
AS 5100.5compression 0.5fcp′0.5f'_{cp} or 0.6fcp′0.6f'_{cp} (8.1.6.2); tension 0.25fcp′0.25\sqrt{f'_{cp}} (8.6.2.1)tension 0.25fc′0.25\sqrt{f'_c}, or 0.5fc′0.5\sqrt{f'_c} with bonded steel (8.6.2.1); compression 0.45fc′0.45f'_c under permanent load
CSA A23.3compression 0.6fci′0.6f'_{ci}; tension 0.25fci′0.25\sqrt{f'_{ci}}, or 0.5fci′0.5\sqrt{f'_{ci}} at the ends of simply supported members (18.3)compression 0.45fc′0.45f'_c sustained and 0.6fc′0.6f'_c total; tension 0.5fc′0.5\sqrt{f'_c}
AASHTO LRFD (US) and EN 1992the limits of the standard with their clausesthe limits of the standard with their clauses
CSA S6stresses listed with the clause to checkstresses listed with the clause to check

AS 3600 is the default for an AS section without a bridge template, and AS 5100.5 the default with one. The stresses are a design aid for the section; the time-dependent losses are the percentages you enter, not a calculation of creep, shrinkage and relaxation.

6.8 Auto-select lists

Model > Auto select lists groups sections into a list, for example all UB sections from 250UB25.7 to 460UB82.1. A member given the list name instead of a section is analysed with the median section of the list by weight until it is designed. The design then picks the lightest section of the list that passes, and the analysis and design are repeated until the analysis sections and the design sections agree. The model check and the run say which section each member was analysed with.

6.9 Area sections

Model > Area sections defines the section of an area:

TypeBehaviour
shell-thinmembrane and bending; Kirchhoff plate theory (no transverse shear deformation)
shell-thickmembrane and bending; Mindlin plate theory (with transverse shear deformation)
plate-thinbending only, Kirchhoff
plate-thickbending only, Mindlin
membranein-plane only

Each area section has a material, a membrane thickness tmt_m (in-plane stiffness, mass and self weight) and a bending thickness tbt_b (bending stiffness; equal to tmt_m when not given), and optional property modifiers (Section 7.7). An area that names a section takes its type, thicknesses and material from it; an area without a section keeps its own type, thickness and material. Chapter 10 describes the elements behind each type.